BUCHAREST, ROMANIA · CUSTOM METAL PARTSONLINE QUOTES · €50 MINIMUM

LASERMET / PDF

Technical guides for your parts.

Detailed guides for laser cutting, bending, welding, machining and powder coating. Read the complete chapters online or download the expanded PDF edition in English.

01 / LASERMET · 24 PAGES

Laser cutting

From a DXF file to a manufacturable part

Check sheet metal laser cutting capacity by material ↗

Download full PDF (EN) ↓
01 / How a laser-cut part is made+

From drawing to contour

Laser cutting separates the part from sheet metal along a programmed path. The beam heats the material locally and assist gas helps remove it from the cut. The resulting geometry is flat; the part thickness comes from the selected sheet. This operation produces external profiles, holes, slots, cut-outs and blanks for subsequent operations.

What CAM programming does

The CAD file is checked, nested on the sheet and converted into a machine program. The programmer sets lead-ins, cutting sequence, kerf compensation and any micro-joints. These are process features, rather than details the customer should automatically add to the drawing.

From contour to product

A bracket may require cutting, bending and coating. A flange may need boring, tapping and dimensional inspection after cutting. Identify the function of the part when requesting a quote: the same CAD shape may require different manufacturing routes when tolerances or appearance requirements change.

Illustrative diagram: How a laser-cut part is made
02 / Laser, waterjet or plasma?+

Choosing a technology

This comparison helps select a suitable process; it is not an inventory of LaserMet machines. For the service covered by this guide, LaserMet confirms laser cutting within the stated limits. Requests requiring another process are assessed separately.

Why the same rules cannot be transferred

Cut width, heat-affected zone, taper and edge quality depend on the process. Results obtained on one machine or material do not automatically define the result for another setup. Compare costs for the complete part, including finishing and precision operations.

Laser, waterjet or plasma?
ProcessCharacteristicsWhen to consider it
LaserLocal heating, 2D profiles; process-dependent kerfSheet metal, parts with many profiles and details
WaterjetJet cutting, possibly with abrasive; without the heat-affected zone associated with laser cuttingMaterials or geometries where thermal effects are critical
PlasmaThermal process for conductive materials; different detail and edge characteristicsParts where thickness and cost matter more than fine details
03 / LaserMet capacity and sheet format+

Working format

3,000 × 1,500 mm. The part must allow process margins and support; sheet format does not automatically equal the maximum usable part size.

Maximum thicknesses

Steel: 12 mm. Stainless steel: 8 mm. Aluminium: 6 mm. Grade, material condition and availability are confirmed in the quote. State, for example, S235JR or 304 stainless steel, rather than simply “metal”.

Process result

Laser cutting produces flat profiles. Threads, precision bores, chamfers and sealing surfaces may require separate operations. Specify edges and appearance in the drawing.

LaserMet capacity and sheet format
MaterialMaximum laser thicknessNominal working format
Steel12 mm3,000 × 1,500 mm
Stainless steel8 mm3,000 × 1,500 mm
Aluminium6 mm3,000 × 1,500 mm
04 / Raster, vector and 3D models+

Raster: an image is not manufacturing geometry

JPEG, PNG and scans are made of pixels. They help identify appearance or discuss an idea, but do not reliably define dimensions and cutting coordinates. An enlarged or reduced photograph can retain its appearance while losing scale. Redraw and check dimensions before production.

Vector: coordinates and profiles

DXF and DWG can contain lines, arcs and polylines with measurable dimensions. However, a vector file can contain open contours, duplicate lines, blocks or incorrectly scaled geometry. The correct format is necessary, but does not by itself guarantee a correct drawing.

3D model: shape plus instructions

STEP/STP represents solid geometry and is useful for bent or machined parts and assemblies. Also specify tolerances, threads and finishes in the dimensioned PDF. STL describes a mesh and does not replace a precision solid model for this quotation workflow.

Raster, vector and 3D models
FileRecommended role
DXF2D cutting profile, in mm at 1:1 scale
STEP / STP3D geometry for checking and multiple operations
Dimensioned PDFMaterial, tolerances, revision, finish and instructions
ImageVisual reference; verified geometry is required
Illustrative diagram: Raster, vector and 3D models
05 / CAD export: steps that prevent errors+

DXF at 1:1 scale

Export in millimetres, with one part per file and closed contours. Remove duplicate lines, isolated points and zero-length segments. Check a known dimension after export.

Separate geometry from instructions

The cutting DXF contains the profile. The dimensioned PDF contains tolerances, material, revision and finish. Put bend or marking lines on separate layers and identify them explicitly.

Other files you can send

STEP for 3D geometry; DWG and PDF for assessment. A photograph or scanned PDF requires redrawing and dimensional verification. Instant estimates are available for eligible DXF files; production follows technical review.

One system of units

Check both model units and export settings. A 100 mm dimension exported in inches may be misinterpreted if the unit is not preserved. Measure a known dimension in the reimported file; the filename does not prove the scale.

Compatibility

For native SOLIDWORKS, Inventor or other models, also export STEP. For 2D drawings, export DXF. This reduces dependency on software versions and proprietary features. Accepting a file does not mean every format qualifies for instant pricing.

06 / CAD software and choosing an export+

No particular application is required

LaserMet needs geometry and verifiable requirements, rather than a particular design program. You can work in a 2D application or 3D modeller, then export neutral files. A native file may help with changes, but also send DXF or STEP together with a dimensioned PDF for assessment.

Flat pattern versus presentation drawing

For bent sheet metal, export the flat geometry from a verified unfolding function, rather than a projected view of the bent part. Decide whether bend lines are excluded from the cutting DXF or retained on a separate layer with explicit instructions. Do not automatically export the bounding box as a cutting path.

Checking after export

Open the exported file in a new document. Check scale, contours and the distinction between cutting lines and instructions. When exporting from a presentation sheet, sheet scale may affect the result; a reference dimension measured in the DXF is more reliable than its on-screen appearance.

CAD software and choosing an export
Application / workflowUseful exportCheck
AutoCAD / 2D drawingDXF of flat geometryUnits, 1:1 scale and selected objects
SOLIDWORKS / sheet metalFlat-pattern DXFBend lines, contours and revision
Inventor / model and sheet metalSTEP; flat-pattern DXFFinal geometry and export scale
Other CAD applicationsDXF / STEP + PDFCompatibility and reimported dimensions
07 / Cleaning geometry and organising layers+

Cutting contours

Keep the geometry flat, at the same Z level, with every contour closed. Remove duplicate lines and partially overlapping segments; they can change contour recognition and calculated length. Check self-intersections, very short arcs and polylines with excessive unnecessary points.

Separate instructions

Dimensions, title blocks, centre lines, hatching and auxiliary views belong in the PDF. For marking or bending, use clearly named separate layers and explain the operation in the request. A red line is insufficient if colour is lost during export or the application interprets it as a cutting path.

Several parts in one file

Preferably send each part separately. If supplying a combined file, explicitly identify each part and its quantity; their arrangement on screen is not the ordered quantity. Do not duplicate geometry instead of providing a parts list.

Cleaning geometry and organising layers
ElementIn the cutting DXF?
External contour and openingsYes, closed and without duplicates
Dimension lines / title blockNo; in the PDF
Bend lineSeparate layer, with instructions
Marking / engraved textSeparate layer, with the operation identified
Points and auxiliary profilesRemove unless they serve a process purpose
Illustrative diagram: Cleaning geometry and organising layers
08 / Tolerances: what to dimension and confirm+

A nominal dimension is not an acceptance range

A 100 mm dimension describes the reference size. The tolerance establishes the permissible range. Specify applicable general tolerances and highlight functional exceptions. An indicative value of ±0.2 or ±0.25 mm does not automatically apply to all LaserMet parts.

Size, form and position

Hole diameter, axis position, plate flatness and edge perpendicularity are different requirements. A part can have the correct diameter but an unsuitable assembly position. Identify measurement datums and avoid contradictory closed dimension chains.

Surface quality and inspection

Identify the visible face and the surface on which a critical dimension is checked. A cut edge may have striations, burrs or taper; assess these for the material and thickness. For fit bores, the solution may be cutting a blank followed by machining, rather than promising identical precision throughout the thickness.

09 / Kerf: cut width and compensation+

What kerf means

Kerf is the width of material removed by the process. It is neither sheet thickness nor a general tolerance. It depends on material, thickness, configuration and parameters. Do not use a fixed 0.2 or 0.3 mm value for all parts or transfer a value from another technology.

Nominal drawing, compensation in CAM

The customer provides the desired contour size. Programming offsets the path so that the resulting edge meets the agreed geometry. Manual compensation added in CAD can accumulate with CAM compensation, producing an oversized part or undersized hole.

Features close to the kerf width

A single-line cut does not automatically define a functional slot of precise width. If a slot must have width s, draw both edges and the ends. Extremely narrow slots, fragile islands and small details require checks of piercing and heat evacuation.

Illustrative diagram: Kerf: cut width and compensation
10 / Holes: diameter, webs and edges+

Define what you measure

Use d = diameter, t = thickness, e = clear distance between the cut hole and the part edge, and p = web between two holes. Centre-to-edge distance is not the same as e: for a circle it is e + d/2. Confusing these radically changes the geometry.

Preliminary LaserMet criteria

As a conservative initial design screen, start from d ≥ t, e ≥ t and p ≥ t. These are recommendations for initial assessment, not guaranteed process minima or a strength calculation. Holes smaller than sheet thickness, narrow webs and dense perforations can be submitted for review; the workshop determines manufacturability.

Why the remaining material matters

Closely spaced holes and thin edges can be affected by heat and become fragile during handling. For mechanically loaded parts, web size must also be established through structural design. A cutting criterion does not verify bolt loading or in-service part strength.

Holes: diameter, webs and edges
SymbolDefinitionExample at t = 3 mm
dHole diameterPreliminary starting point: d ≥ 3 mm
eClear hole-to-edge distancePreliminary starting point: e ≥ 3 mm
pWeb between contoursPreliminary starting point: p ≥ 3 mm
cCentre-to-edge distancec = e + d/2
Illustrative diagram: Holes: diameter, webs and edges
11 / Slots, notches and narrow cut-outs+

A slot is an area, not a line

Draw nominal slot width and length, including end shape. For an adjustment slot, check bolt diameter, washer access and usable travel length. A very long slot can weaken a part even if it can be cut.

Piercing at the start of a contour

The process requires an entry point. Lead-in and sequence are set in CAM; a narrow slot may provide insufficient space. An enlarged end can be a solution, but do not add it automatically: enlargement must be compatible with part function and appearance.

Edge notches

Deep notches, very sharp corners and slots close to the contour can concentrate stress and leave thin features. Select radii or reliefs for the assembly. For a locating function, dimension from a datum rather than specifying only cut-out width.

Illustrative diagram: Slots, notches and narrow cut-outs
12 / Corners and assembly reliefs+

Internal versus external corners

A very sharp internal corner can prevent insertion of an edged component or concentrate stress. A circular dog-bone relief or controlled notch can help assembly. Dimension the shape in the drawing; do not add it to a functional part without agreement.

Radius and strength

Rounding a corner can reduce sensitivity to stress concentration, but does not by itself verify part strength. For a loaded part, choose radius based on function, material, loads and assembly space. No universal thickness multiplier defines the radius for every material and function.

Edges accessible during handling

Exposed external corners can be rounded or deburred. State whether burr removal is sufficient or a controlled radius/chamfer is required. Deburring does not automatically produce the same dimension as a machined chamfer.

Illustrative diagram: Corners and assembly reliefs
13 / Tab-and-slot joints and locating protrusions+

Clearance must be defined

For a tab of width b in a slot s, nominal total clearance is j = s - b. Assembly depends on tolerances of both parts, burrs, flatness and coating. For production runs, validate the joint using the actual material and finish before release.

Local nodes / protrusions

Small protrusions can localise contact or increase friction in a joint. They do not guarantee retention or replace calculations for a loaded joint. An oversized node may block assembly or distort the plate; an undersized one may be removed or affected during cutting.

Locating for welding

Tabs can help assemble subassemblies repeatably, but access for welding and fixtures must remain. Check whether they are visible in the product and whether they must be removed. Do not request an interference press fit followed by welding without assessing the effect on final position.

Illustrative diagram: Tab-and-slot joints and locating protrusions
14 / Cut-out text and shapes with islands+

Letters with enclosed areas

In letters such as A, B, D, O, P, Q and R, internal islands detach unless connected by bridges. For negative text in sheet metal, use a stencil design or add bridges compatible with the desired appearance. The same principle applies to logos with isolated areas.

Convert fonts to outlines

Editable text can depend on installed fonts and may be substituted when opened. Export letters as vector geometry. After conversion, check closed contours, duplicates and every island; an “explode” command alone does not guarantee clean geometry.

Legibility and detail

Check minimum stroke and bridge widths at actual scale. Font size is not the width of the thinnest feature. Large letters in a fine font can be harder to manufacture than smaller letters with thick strokes. Approve a sample before production if appearance matters.

Illustrative diagram: Cut-out text and shapes with islands
15 / Marking, identification and packaging+

Identify the operation, not just the colour

Separate marking text from the cutting path. Explicitly state MARKING, position, size and face in the request. Availability is checked for the project material and finish; this guide does not promise decorative engraving or identical contrast on every surface.

Files and revisions

For logos or graphics, provide vector geometry and a reference PDF. For a part code, specify exact text and revision. If marking must remain legible after coating, assess this before selecting the method and operation sequence.

A label is not permanent marking

Packaging labels help receiving, kitting and batch identification. Specify whether each part, bag or box needs a label. Include code, quantity, revision and any batch number; do not assume full traceability unless agreed in the quote.

Marking, identification and packaging
SolutionRoleWhat to specify
Marking on the partDirect identificationText, position, face, permanence and appearance
Label on the partRemovable identificationAdhesive / permitted area / information
Packaging labelReceiving and separating partsCode, revision, quantity, kit / batch
16 / Materials: grade, condition and surface+

Sheet steels

S235JR and S355J2 are structural steel grades; DC01 is steel for cold forming. DX51D identifies a category used for coated products, with coating type and mass specified separately. These designations are not interchangeable, even at the same thickness. For high-strength steels, request separate assessment of subsequent operations.

Stainless steel

304 / 1.4301 and 304L / 1.4307 are distinct designations; 316L commonly corresponds to 1.4404. “2B”, “brushed” and “bright” describe the surface and do not replace the grade. Also state brushing direction, visible face and protective film. Film compatibility with cutting is confirmed.

Aluminium

Specify alloy and temper, for example EN AW-5754 H111. Two aluminium sheets of the same thickness can behave differently in bending, welding and finishing. For a part involving multiple operations, select material for the entire route, rather than only cutting.

Materials: grade, condition and surface
FamilyExample specificationsDetail not to omit
SteelS235JR / S355J2 / DC01Thickness, condition, protection
Stainless steel304 / 304L / 316LSurface, film, direction
AluminiumEN AW-5754 H111Alloy, temper, subsequent operations
17 / Common thicknesses and availability+

A reference table, not an inventory

The table lists common examples for preparing a request; availability depends on the required grade and condition, supplier and batch. It does not represent LaserMet stock. Thicknesses above cutting limits are not included as a standard offer in this guide.

Format and stock tolerances

The 3,000 × 1,500 mm format is the nominal working limit. Material may also come from other compatible formats, such as 2,000 × 1,000 or 2,500 × 1,250 mm, depending on supply. Actual thickness and flatness follow stock tolerances, which can affect joints and bending.

Customer-supplied material

State grade, thickness, condition, surface and available documents. Rusted, distorted, unidentified material or material with an unknown coating requires assessment. Do not plan production on the assumption that any sheet offcut matches the quality specified in the design.

Common thicknesses and availability
FamilyExamples of common thicknesses, mmLaserMet maximum
Structural steel2; 2.5; 3; 4; 5; 6; 8; 10; 1212 mm
Forming steel0.5; 0.8; 1; 1.2; 1.5; 2; 2.5; 3Within the 12 mm limit
Stainless steel0.5; 1; 1.5; 2; 2.5; 3; 4; 5; 6; 88 mm
Aluminium0.5; 1; 1.5; 2; 2.5; 3; 4; 5; 66 mm
18 / Deburring, edges and the visible face+

What is removed

Cutting can leave burrs, local dross, lead-in marks or micro-joint marks. Specify the required treatment: burr removal, a handling-safe edge, local grinding or a controlled chamfer. These requirements involve different operations and times.

Tolerances after finishing

Edge treatment can alter local dimensions. Do not combine a functional edge with uncontrolled grinding when fit is critical. Dimension the radius or chamfer where important and state whether dimensions are checked before or after deburring.

Sensitive surfaces

For brushed stainless steel or film-covered sheet, identify the visible face, direction and acceptable scratches. Temporary protective oil on steel is not a final coating and may need degreasing before painting or welding. Select protection and packaging together with the required finish.

Deburring, edges and the visible face
RequirementMeaning for quotation
DeburringRemoval of residual material from the edge
Dimensioned chamfer / radiusControlled geometry; operation to be checked
Cosmetic grindingDefined appearance and acceptable surfaces
Temporary protectionStorage / transport; distinct from final coating
Illustrative diagram: Deburring, edges and the visible face
19 / Inserts, nuts and standoffs+

Choose the right family

Self-clinching nuts, rivet nuts, weld nuts, cage nuts and standoffs do not share the same installation method. Specify a code or functional requirement, material and installation direction. The workshop checks availability and the operation before confirmation.

Design the hole for the component

Hole diameter and tolerance, minimum thickness, substrate hardness and edge distance come from the insert datasheet. Do not confuse hole-axis-to-edge distance with clear distance from the contour. Do not use thread diameter as installation-hole diameter.

Sequence and surfaces

For press-in inserts, changing the hole edge or installing after coating may affect retention; check conditions for the selected type. Do not automatically deburr or countersink holes dedicated to inserts. Check pressing access and whether bending deformation may affect the hole.

Inserts, nuts and standoffs
ElementInformation to supply
Press-in nut / studCode, hole, thickness, hardness, direction
Rivet nutCode, grip range, hole, access
Weld nutMaterial, position, weld and protection
Standoff / cage nutMounting interfaces and available space
Illustrative diagram: Inserts, nuts and standoffs
20 / Planning operations after cutting+

Bending

Send the final model and drawing with radii, angles and dimensions. The flat pattern is checked against tooling and actual bending data. Holes near the deformation zone may require relocation, relief or later machining; cuttable geometry does not automatically guarantee bendable geometry.

Welding and machining

For assemblies, include the parts list, locations and welds. For bores, threads or precision surfaces, specify operation and tolerance. Some cases need machining allowance; agree it with the workshop rather than modifying the final profile without notice.

Coating and assembly

Coating changes clearances and diameters. Identify threads, electrical contacts and sealing surfaces requiring masking. If two parts are assembled after coating, check clearance in the final condition. Include assembly and packaging in the same request for a complete price.

21 / Reducing cost while retaining function+

What affects price

Cost depends on material and consumption, contour length, number of piercings, thickness, setup time and subsequent operations. A small, heavily perforated plate may need more cutting time than a larger plate with a simple outline. Weight alone does not describe total cost.

What can be optimised

Use common thicknesses and grades where function permits. Remove nonfunctional details, rather than necessary holes. Group quantities by material and revision, and request prototype and production pricing separately. An approved production sample reduces the risk of reworking an entire batch.

Before confirming an order

Check whether the quote includes material, cutting, deburring, bending, welding, inserts, finishing, inspection and transport. LaserMet minimum order value is €50 excluding VAT; this does not replace calculation for each part. Online estimates for eligible files are followed by technical review before production.

Reducing cost while retaining function
FactorUseful action
Many internal contoursReview the purpose of perforations
Multiple revisionsRetain only the ordered revision
Unnecessary tolerancesLimit precision to actual functions
Production runApprove the sample and inspection criteria
22 / Complete checklist and example request+

Files

Clean DXF at 1:1 scale; STEP for 3D geometry where applicable; dimensioned PDF with material grade, thickness, tolerances and revision. The same code must identify the same part in every document. Drawing and model must not contain conflicting revisions.

Manufacturing and appearance

State quantity per part, subsequent operations, visible face, deburring level, inserts and marking. For coating, provide RAL, texture, gloss and masking. For fit components, state the final condition in which the dimension must be met.

Delivery and documents

State requested deadline, packaging and address. Material certificates, inspection reports and traceability must be explicitly requested and confirmed in the quote. For kits, attach the parts list per kit and number of kits; quantities shown in an image are not an order list.

Send your part for a quote ↗

02 / LASERMET · 14 PAGES

CNC bending

Clear bend radii, hole positions and flat patterns

Download full PDF (EN) ↓
01 / The model and drawing+

Recommended package

Send the STEP model of the finished part and a dimensioned PDF. Include material, thickness, internal radius, angles and quantity. A DXF flat pattern is useful, but must be checked against production tooling.

Unambiguous dimensions

State whether lengths are internal or external. For angles, show the final angle between faces. Identify the visible face and any surfaces where tooling marks are unacceptable.

Capacity

Permissible length, thickness and geometry depend on material, required force and tooling. Laser cutting limits are not bending limits. Capacity is confirmed for each part.

02 / Radii and unfolding+

Internal radius

A radius of the order of sheet thickness can be a starting point for some ductile sheets, but does not apply universally. Alloy, delivery condition and rolling direction can require larger radii.

Do not set a universal K-factor

The flat pattern depends on achieved radius, die, punch and process. A K-factor taken from CAD must be verified; parts with critical dimensions may need trials and corrections.

Standardise radii

Where function permits, use the same radius and common angles. Reduce tooling changes and avoid very short or closely spaced bends without checking access.

03 / Holes, reliefs and access+

Holes near a bend

As a conservative preliminary check, keep the hole-edge-to-bend-tangent distance at least 2t. Radius and tooling may require more. Functional holes in the deformation zone may need machining after bending.

Reliefs at bend ends

Provide reliefs extending beyond the deformation zone and avoid corners that can initiate cracks. Agree shape and dimensions with the workshop according to material and tooling.

Tooling access

U-shaped parts, enclosed boxes and return flanges may collide with the punch or machine. Check bend sequence; a part may require special tooling or division into subassemblies.

Illustrative diagram: Holes, reliefs and access
04 / Air bending and tooling selection+

Punch, die and part

In air bending, the sheet is supported by the die and pressed by the punch. The achieved radius and final angle depend on die opening, material, thickness and stroke. A radius modelled in CAD is not automatically achieved simply by selecting a punch with the same radius.

Why each geometry is checked

Required force increases with material strength, thickness and bend length. A short, thick part cannot be compared directly with a long, thin one. Usable machine length does not guarantee every bend along that length. Tooling and access form part of technical confirmation.

Marks and protection

Tooling contact can leave marks, especially on cosmetic surfaces. Identify the visible face and film or protection requirements. Do not specify an unknown film without checking it; it can affect both process and appearance.

Illustrative diagram: Air bending and tooling selection
05 / Radius, rolling direction and springback+

Material behaviour varies

Alloy, delivery condition, thickness and rolling direction affect bendability. Forming steel, stainless steel and aluminium do not automatically share the same minimum radius. On a low-ductility material, too small a radius can cause cracks even when the CAD geometry is valid.

Springback

After the force is removed, the part can recover partially through elastic springback and the angle changes. The workshop compensates the process for the required final angle. Do not send an “overbent” model to compensate springback without declaring the change, since programming may apply further compensation.

Final drawing and trial

Define the accepted final geometry in the model and drawing. For sensitive materials or geometries, a trial using the actual batch helps determine settings. Acceptance criteria should include angle, final dimensions and appearance, rather than only matching the flat pattern.

Radius, rolling direction and springback
FactorPossible effect
Alloy and conditionPermissible radius and ductility
Rolling directionDifferent sensitivity to cracking
Thickness / batchRadius and angle variation
SpringbackRequires process compensation
06 / Flat-pattern calculation: BA, BD and K-factor+

Neutral axis

During bending, the outside stretches and the inside compresses. The K-factor expresses the approximate neutral-axis position within the thickness. In a simplified model, neutral arc length is BA = α × (R + Kt), where α is the bend angle in radians, R the internal radius and t the thickness.

The formula has conditions

BA is bend allowance, the bend-zone length in the flat pattern. Do not add it directly to two external dimensions if those already include the corner zone. For external dimensions, bend deduction is calculated using the dimensioning convention and corresponding geometric setbacks. CAD and workshop must use the same convention.

Do not use a universal K

A software K value is an assumption until correlated with tooling and material. Production uses validated data. If the workshop recalculates the flat pattern, the finished model and dimensions remain the reference; change the DXF only after clarifying the revision.

Illustrative diagram: Flat-pattern calculation: BA, BD and K-factor
07 / Minimum flange, returns and access+

Flange length

A flange must be supported on the die and positioned. Minimum length depends on tooling opening and shape, rather than thickness alone. A very short flange may fall into the die or need a different manufacturing route. Send its dimension and function before freezing the drawing.

Boxes and U-sections

Check clearance for the punch and part body at every stage. A bend that is feasible individually may become impossible after an earlier flange is formed. Radius, box depth, returns and thickness determine the need for special tooling.

Backgauge access

The part needs a stable locating datum. Cut-outs, angled flanges and asymmetric parts may limit backgauge contact. Designing a reference area or changing bend order can improve repeatability.

Minimum flange, returns and access
GeometryRequired check
Short flangeSupport on die
Deep U-sectionPunch collision
Return flangeAccess and sequence
Asymmetric partBackgauge datums
Illustrative diagram: Minimum flange, returns and access
08 / Holes near bends: the correct distance+

Measure from the bend tangent

The recommended hole-edge-to-bend-tangent distance is not the distance to an arbitrarily drawn axis in the flat pattern. State the reference explicitly. For a circular hole, centre-to-tangent distance equals clear distance plus d/2.

A preliminary criterion, not an absolute rule

The 2t criterion used for preliminary screening must be checked against radius and tooling. A hole can become oval or pull the edge if the deformation zone intersects it. The permissible limit cannot be determined solely from an image of the part.

Design solutions

Move the hole, change radius or flange, add a verified relief or make the hole after bending. Choose according to function: a clearance bolt hole has different requirements from a locating bore. Nearby inserts also require an access check.

Illustrative diagram: Holes near bends: the correct distance
09 / Bend reliefs and enclosure corners+

Why they are needed

When one sheet area bends while its neighbour remains flat, material at the boundary can stretch, tear or bulge. A relief separates the forming zone. Design its shape and length relative to radius and thickness, avoiding a very fragile edge.

Two flanges at the same corner

On an enclosure, neighbouring flanges may overlap or leave gaps. Include thickness, radius and assembly clearance in the finished model. Do not construct a box from zero-thickness faces or assume every corner closes without cuts or welding.

Corner function

For a sealed box, incorporate the relief into the closure and welding solution. For a cosmetic enclosure, assess the visible gap and grinding. For a mechanical support, check remaining material; a relief must not weaken a loaded zone without control.

Illustrative diagram: Bend reliefs and enclosure corners
10 / Tolerances after bending and assembly+

Individual dimensions and accumulated deviations

Length and angle deviations can accumulate in a part with several bends. A dimension between two holes on the same flat face differs from the distance between holes on separate flanges. Identify the surfaces and datums determining assembly.

Effect of angular deviation

Angular deviation moves a flange end. Approximate transverse displacement for a flange of length L and a small deviation δ is L × sin δ. A long flange is more sensitive than a short one at the same angle.

Inspection dimensions

Dimension clearly after bending and before/after finishing. If function is assembly fit, an agreed trial or gauge can be more relevant than excessive dimensioning of every face. Avoid contradictory dimensions and define requirement priorities in the drawing.

Illustrative diagram: Tolerances after bending and assembly
11 / Complete example: bracket and enclosure+

L-bracket

Provide the final model, material, thickness, internal radius, final angle and flange dimensions. Identify mounting holes and their distance from the tangent. If lengths are external, state this convention; do not also supply a flat pattern based on another radius without explaining it.

Enclosure with several bends

Include covers and interfaces in the assembly. Check screw access, clearances, inserts and corners needing welding. For visible faces, specify orientation, surface direction and areas without marks. Use the same revision for model, drawing and flat pattern.

Prototype and production

The prototype checks actual assembly and tooling access. After acceptance, fix revision, material, finish and inspection criteria. A flat-pattern correction must not be applied only to a DXF while leaving the final drawing outdated.

Complete example: bracket and enclosure
PackageContents
GeometryFinal STEP + dimensioned PDF
ProcessBends, inserts, welds, finish
InspectionFinal dimensions and critical angles
ProductionAccepted revision and quantity
12 / Checklist and cost+

Checklist

Final STEP; dimensioned PDF; material; thickness; radii; angles; internal/external dimensions; visible face; functional tolerances; quantities and revision.

Practical example

On 2 mm sheet, a hole edge 1 mm from the bend tangent requires revision. A 4 mm distance passes only the preliminary 2t check; the workshop still checks tooling and radius.

Reducing cost

Standardise radii and orientations, restrict tight dimensions to actual functions and verify the flat pattern before production release. Dimensions after bending have different conditions from those of a flat profile.

Send your part for a quote ↗

03 / LASERMET · 14 PAGES

Welding and subassemblies

Clear drawings for laser, MIG/MAG and TIG welding

Download full PDF (EN) ↓
01 / What to send to the workshop+

Assembly definition

Send the STEP model, assembly drawing and parts list. Specify materials, thicknesses, quantity and functional surfaces. Number subassemblies for clear identification.

Weld definition

State joint type, position, size and weld lengths. If using symbols, identify the drawing standard. “Fully welded” does not adequately define functional requirements.

Process selection

Laser, MIG/MAG and TIG have different requirements for joint gap, access and material. Selection is confirmed after reviewing geometry and appearance, strength or leak-tightness requirements.

02 / Joint gap and access+

Part fit-up

Control gap, flatness and edge positioning. Do not transfer MIG/MAG joint-gap tolerances to laser welding. For laser welding, fit-up must be assessed for the actual configuration.

Access for manufacturing

Leave space for the welding head and fixtures. A weld drawn inside a closed corner may be inaccessible; check assembly sequence before finalising parts.

Clean surfaces

State whether material is galvanised, painted or oiled. Preparation and restoration of protection around the joint are established in the quote; the final finish follows the necessary operations.

03 / Distortion and tolerances+

Welds sized for function

Excess deposited metal can increase shrinkage and distortion. Weld sizing belongs to the design; the workshop does not arbitrarily reduce specified welds.

Positioning and sequence

Fixtures and a balanced sequence can control distortion. Dimension reference points and final dimensions after welding. Provide allowance where subsequent machining is needed.

Sealing and verification

For containers or leak-tight assemblies, specify medium, pressure and verification method. Agree inspection and documentation requirements before production; they cannot be assumed from the model.

Illustrative diagram: Distortion and tolerances
04 / Laser, MIG/MAG and TIG: process selection+

Selection starts with function

The process is selected for material, thickness, joint, access, productivity and final requirements. A process name does not guarantee penetration, strength, leak-tightness or appearance. Load-bearing or sealed parts need design and verification requirements defined before production.

Laser

Energy is concentrated in a small area, but the result depends on edge fit-up, joint position, material and configuration. Filler use or other operating modes change process requirements. Do not copy a joint gap from arc welding to laser welding without assessment.

MIG/MAG and TIG

MIG/MAG uses a continuous wire electrode and shielding gas; gas type and filler are selected for the material. TIG uses a non-consumable electrode and can include separate filler. Productivity and weld-pool control differ. The workshop proposes the appropriate route, while the drawing defines the required result.

Laser, MIG/MAG and TIG: process selection
ProcessImportant checks
LaserGap, positioning, access, penetration and appearance
MIG/MAGGap, filler, access, spatter and distortion
TIGAccess, preparation, filler, shielding and time
05 / Butt, lap and T-joints+

Butt joint

Align the ends and define gap and preparation according to process and thickness. If full penetration is required, state and verify it. Drawing a line between two parts does not automatically define a fully penetrated joint.

Lap and T-joints

For a lap joint, contact length, access and any gap matter. In a T-joint, effective weld thickness and length define the weld requirement. Do not size a weld from a rendering. Identify whether it is single-sided, double-sided or limited to particular segments.

Closed corners

On enclosures, head access and assembly order are decisive. Check access to the root and feasibility of later finishing. For a sealed product, the weld path must be continuous where necessary, with the verification method explicitly agreed.

Illustrative diagram: Butt, lap and T-joints
06 / Defining the weld on a drawing+

Dimensions and symbols

For a fillet weld, throat thickness a and leg length z are different dimensions. For an idealised 90° section with equal legs, a ≈ z/√2. State the correct symbol and size, position, length and any pitch; the workshop checks interpretation before production.

Length, continuity and side

Identify exactly the welded areas, application side and any interruptions. “30 mm weld” may mean one segment, rather than the entire edge. For intermittent welding, define segment count or pitch and location; do not leave this to interpretation of a photograph.

Functional requirement

State whether the weld serves positioning, strength, sealing or appearance. A weld ground flush can have a different final section from an exposed weld. Material removal after welding must be approved for the function and design.

Illustrative diagram: Defining the weld on a drawing
07 / Joint gap, fit-up and part preparation+

Flatness and alignment

Edges must allow repeatable positioning. Check cutting and bending deviations, stock distortion and fixture contact. Forcing nonconforming parts together can introduce stresses and hide a dimensional problem that reappears after release.

Preparation and contamination

Removal of oxides, grease, paint or coatings is determined for the material and process. State whether material is galvanised or has unknown protection. The prepared area must permit welding and finish restoration; a painted surface is not assumed ready for welding.

Gap is a process condition

Opening, angle and bevel are selected for the joint, thickness and procedure. We do not publish a universal maximum gap for LaserMet. If a part needs laser welding, discuss the model and fit-up tolerances before manufacturing all production parts.

Joint gap, fit-up and part preparation
ProblemPossible consequence
Variable gapUneven penetration / appearance
Misaligned edgesChanged position and section
Contaminated surfaceAffected quality and finish
Forced fit in fixtureStress and springback after release
08 / Fixtures, tack welding and weld sequence+

Positioning in a fixture

Establish datums determining final geometry and head access. Supports must allow handling and any necessary movement. A fixture improves repeatability but cannot compensate without limit for parts that do not match the drawing.

Tack welding

Tacks hold position before the final weld and form part of the manufacturing plan. Their location and integration into the final weld are established technically. Visible tacks that need removal or finishing must be included in appearance requirements.

Sequence and distortion

Heat and shrinkage can alter angles and dimensions. Segment sequence, alternating areas and fixtures are selected for the actual geometry. For a long or thin-sheet part, a trial is useful to check geometry after cooling and release.

Illustrative diagram: Fixtures, tack welding and weld sequence
09 / Materials and finishing after welding+

Steel

Material and condition affect preparation, filler and any process measures. High-strength steels or material combinations need separate assessment. This quotation guide does not replace selection of a suitable welding procedure.

Stainless steel and aluminium

Specify grade, condition and surface requirements. For stainless steel, describe the difference between exposed welds, ground welds and restored brushed surfaces. For aluminium, alloy and temper are essential; compatibility and results are checked for the project.

Finishing and machining

Grinding can change weld section and edges. Precision bores or surfaces may be machined after welding where function requires it. Plan final coating after welding and preparation; substrate roughness and marks may remain visible unless corrected.

Materials and finishing after welding
RequirementNecessary detail
Exposed weldAccepted appearance and visible face
Ground flushPermitted areas and final geometry
Brushed stainless steelDirection and restoration method
Precision surfaceMachining before / after welding
10 / Inspection: dimensions, appearance and leak-tightness+

Dimensional inspection

Define final dimensions after cooling, measurement datums, flatness and relationships between parts. Frame diagonals and hole alignment can be critical. For an enclosure, cover position and gasket plane may matter more than overall external dimensions.

Weld quality

External appearance alone does not prove penetration or absence of internal defects. If special inspection, acceptance levels or qualification documents are needed, request them before quotation and obtain explicit confirmation. A faster process does not remove verification needs.

Leak-tightness

State medium, pressure or vacuum, duration and test method where defined by the design. Review the requirement with the technical lead. Visual inspection or a simple test is not equivalent to every pressure-vessel requirement.

Inspection: dimensions, appearance and leak-tightness
CheckPurpose
DimensionalGeometry and assembly
VisualAppearance and visible defects
Requested special inspectionCharacteristics agreed for the design
Leak testSpecific function and acceptance criterion
11 / Example subassembly quotation request+

Define the deliverable

Instead of “welded frame”, supply assembly code, drawing, parts list, materials and revisions. State whether LaserMet supplies the complete subassembly or welds customer-supplied parts. Identify included cutting, bending, drilling and coating operations.

Assembly requirements

State hole positions, seating plane, contact points and permissible distortion. Include mating parts if available to check screw access and function. A rendering helps orientation, but a dimensioned drawing remains necessary.

Production and acceptance

Separate the prototype from annual production and delivery batches. A fixture can have a setup cost and offer production benefits. After prototype approval, retain the same requirements and documents for the batch; any part change needs a new revision.

12 / Assembly acceptance+

Checklist

Assembly drawing; parts and revisions; materials; weld definitions; final dimensions; appearance; finish; inspection requirements and requested documents.

Function and appearance

A surface ground flush has different requirements from an exposed weld. Identify visible areas and where the design permits weld-metal removal.

Cost and repeatability

Use parts that locate easily, reduce reorientation operations and discuss a production fixture. An accepted prototype helps establish criteria before the batch.

Send your part for a quote ↗

04 / LASERMET · 14 PAGES

Mechanical machining

Turning, milling, drilling and threads to drawing

Download full PDF (EN) ↓
01 / Files and requirements+

STEP plus PDF

For 3D design and prototyping, also send the sketch, part function and mounting interfaces. The model describes shape; the drawing specifies tolerances, roughness, threads and measurement datums. Include material grade and condition, quantity and revision.

Functional dimensions

Identify fits and contact surfaces. Very tight tolerances on every dimension may require unnecessary machining and inspection. Establish requirements according to each surface’s role.

Confirmed capacity

Maximum dimensions, materials, precision and required axis count are checked for the part. Do not assume every uploaded geometry can be manufactured by the same route.

02 / Milling and pockets+

Internal corners

A cylindrical cutter leaves a radius in internal corners. Avoid perfectly sharp pocket corners; reliefs can accommodate a rectangular component where function permits.

Depth and access

Deep, narrow pockets need long, less rigid tools. Increase radius and opening where possible. Hidden cavities and undercuts require access checks.

Thin walls

Thin walls can distort during clamping and machining. Permissible thickness depends on material, height and geometry; discuss workholding strategy and operation sequence.

03 / Turning, holes and threads+

Rotational parts

Use coaxial geometry where function permits and specify relationships between diameters. Side holes and non-circular features may require additional operations and setups.

Blind holes

Specify usable cylindrical depth separately from the drill point. Do not implicitly require a flat bottom unless necessary. Long, small holes require chip-evacuation checks.

Threads

State type, diameter, pitch, class and usable length. For example: M6 × 1, usable thread 10 mm; drilling depth is established separately. Specify clearances for the screw and its head.

Illustrative diagram: Turning, holes and threads
04 / Selecting stock and the manufacturing route+

Turning or milling

Turning suits many rotational shapes; milling creates faces, pockets, profiles and other geometry. A part may need both, plus drilling or threading. Do not assume an entire part is produced in one setup because the model is a single solid.

Stock

Select bar, plate, section or cut blank according to dimensions, material and operations. Let the workshop establish process allowances compatible with the final drawing. Undersized stock may prevent workholding; excessively large stock increases consumption and time.

Material and condition

Grade, treatment and delivery condition affect machinability and stability. State whether requirements apply before or after treatment. Do not replace an alloy based solely on appearance; substitutions require explicit acceptance.

Selecting stock and the manufacturing route
ShapeRoute to assess
Shaft / bushingTurning + additional operations
Plate with pocketsMilling, drilling and inspection
Sheet-metal partCutting + local machining
Welded assemblyWelding + final machined surfaces
05 / Pockets: tool radius and depth+

Internal radius

A cylindrical cutter cannot produce a perfectly sharp internal corner. Corner radius must allow access for a sufficiently rigid tool. Where function permits, a larger radius may reduce passes with small tools. Dimension corner reliefs and check against the component entering the pocket.

Depth and narrowness

Depth-to-opening ratio indicates access difficulty but does not by itself establish a universal limit. Long tools may deflect or vibrate, and chip evacuation becomes harder. State whether pocket shape can change without changing function.

Bottom and surfaces

State whether the bottom must be flat, whether a radius is permitted and where roughness is specified. A sealing surface has different requirements from a weight-reduction recess. Do not impose the same roughness on every surface unless needed.

Illustrative diagram: Pockets: tool radius and depth
06 / Holes: drilling, boring and counterbores+

Simple hole and precision bore

A bolt clearance hole and a centring bore have different requirements. For centring, dimension the fit, position and datums. Manufacturing may involve drilling followed by boring, reaming or another operation, according to geometry and tolerance.

Counterbores and countersinks

A cylindrical counterbore defines a head recess or bearing surface. A conical countersink has diameter/depth and angle. Do not confuse a screw-head countersink with a small deburring chamfer. Explicitly dimension functional geometry.

Blind and through holes

State usable depth and whether a conical drill point is allowed. Check remaining thickness to the opposite face or a pocket. Discuss long holes with the workshop; diameter alone does not describe deviation and chip-evacuation risk.

Holes: drilling, boring and counterbores
OperationDrawing requirement
DrillingDiameter, position, through / blind
Boring / reamingFit and inspection datums
Cylindrical counterboreDiameter, depth, face
CountersinkAngle, diameter / depth
Illustrative diagram: Holes: drilling, boring and counterbores
07 / Internal and external threads+

Complete specification

For metric threads, state M, diameter, pitch, class and usable length; for other families identify the standard and required form. A thread drawn in a model can be interpreted differently unless defined in the PDF. Explicitly state left-hand threads.

Usable depth and drilling

In a blind hole, full thread does not automatically extend to drilling depth. Space is needed for tool entry, thread runout and any drill point. Specify the required usable length; the workshop checks depth and remaining material.

Reliefs and assembly

External threads near a shoulder may require relief for the tool and mating-part seating. Check wrench access, screw head and wall thickness. Thread length is sized for material and load; a generic multiplier does not replace calculation.

Illustrative diagram: Internal and external threads
08 / Thin walls, long parts and workholding+

Rigidity

A tall, thin wall may distort under cutting forces or clamping. Minimum manufacturable thickness depends on material, height, shape and access. Sometimes operation sequence changes or supports are used; other cases require geometry revision.

Shafts and bushings

A long, thin shaft may require support, while a thin-walled bushing may distort in a chuck. Specify functional diameters and required concentricity relative to datums. Do not treat clamped dimensions as equivalent to dimensions after release.

Workholding areas

The workshop must hold the part safely and reach its surfaces. Geometry without useful clamping areas may need a fixture or sacrificial allowance. State whether temporary holes or marks on nonfunctional areas are allowed; they are not added arbitrarily.

Thin walls, long parts and workholding
ProblemOption to assess
Flexible wallGreater rigidity / support / different sequence
Long shaftSuitable support and workholding
All surfaces functionalDedicated fixture
Clamping marks unacceptableProtected areas and appearance criteria
09 / Tolerances, datums and roughness+

Size versus geometry

Diameter tolerance does not define concentricity, cylindricity or position. Face flatness alone does not define perpendicularity to an axis. If functional, specify these characteristics in the drawing with identifiable datums and verification conditions.

General dimensions and exceptions

Use general tolerances appropriate to the design and highlight critical dimensions. Tight tolerances may require different tooling, settings, inspection temperatures and measuring methods. LaserMet confirms them per part; this guide does not establish universal precision for all dimensions.

Roughness and marks

Identify surfaces needing roughness control and state the parameter, such as Ra, with units. A “shiny” rendered surface does not specify roughness. Also state chamfers, radii and edges that must not be rounded, so deburring does not affect assembly.

10 / 3D design and prototyping+

Starting from a sketch

Send function, main dimensions, known loads, mating parts and space constraints. Photographs and sketches help, but mounting dimensions must be verified. Defining geometry does not automatically include structural verification or product certification.

What needs approval

Before manufacturing, clarify model, drawing, material, operations and functional criteria. For a replacement part, establish whether to copy measured geometry or design a modified solution. A worn part can provide dimensions that differ from the original drawing.

Prototype versus production

A prototype can validate fit and the manufacturing route. After testing, update every file and approve the production revision. State which tests the customer performs and which checks the workshop performs; a fitting prototype alone does not prove service life.

3D design and prototyping
StageResult to agree
DefinitionFunction, interfaces, dimensions
DesignModel and drawing for approval
PrototypeFit and agreed checks
ProductionAccepted revision and inspection
11 / Cost estimation and a complete request+

More than weight

Time depends on material removal, access, setup count, tools, tolerances and inspection. A light part with deep pockets and many holes may cost more than a heavy part with simple geometry. Stock consumption differs from final mass.

Useful optimisations

Reduce orientations, allow tool-compatible radii and remove unnecessary precision. Avoid nonfunctional thread depths and very fine surfaces where unnecessary. Request a price comparison for actual quantities, rather than only one prototype.

Quotation package

STEP and PDF, material grade and condition, quantity, tolerances, roughness, threads, finish and requested documents. State whether design is included and whether the model is final or can be optimised. Indicative online pricing is technically confirmed before manufacturing.

12 / Inspection and cost reduction+

Checklist

Consistent model and drawing; datums; tolerances; roughness; threads; material and condition; quantity; finish; measurement and traceability requirements.

Revision example

A pocket with sharp internal corners may require another process. Adding a tool-compatible radius, where function permits, simplifies manufacturing.

Cost

Reduce setups, use common holes and threads, and specify fine roughness only where needed. Request prototype and production prices separately; material availability is confirmed.

Send your part for a quote ↗

05 / LASERMET · 14 PAGES

Finishing and powder coating

Appearance, protection and assembly after coating

Download full PDF (EN) ↓
01 / Specify the result+

Final appearance

State RAL colour, texture, gloss and visible faces. RAL code alone does not define texture or gloss. For matching an existing product, provide an accepted sample.

Service environment

State indoor/outdoor use and exposure to moisture and chemicals. Preparation and coating system are selected for material and use; colour does not define corrosion resistance.

Operations before finishing

Plan deburring, welding, grinding and machining before coating. Weld marks or substrate defects may remain visible without appropriate preparation requirements.

02 / Fits and masking+

Coating changes dimensions

The applied layer affects diameters, slots and assembly clearances. Request system thickness in the quote and check final fit. Do not use a universal value for every finish.

Uncoated areas

Identify threads, contact, grounding and sealing surfaces requiring masking. State whether tolerance is required before or after finishing.

Hanging points

Parts need positioning during the process. Agree hanging holes or points and areas where marks are acceptable, especially on design features.

03 / Material and geometry+

Substrate preparation

Steel, stainless steel and aluminium need appropriate preparation. Do not prescribe identical preparation for every material. State existing coatings and any repairs.

Edges and cavities

Very sharp edges and difficult-to-reach areas can complicate uniform coating. Provide safe edges and discuss deep cavities during design.

Hollow assemblies

For sections and enclosed volumes, assess ventilation, drainage or access-hole needs with the workshop according to the process. Do not close the geometry before this check.

Illustrative diagram: Material and geometry
04 / Coating system, colour and environment+

The system is more than RAL

Electrostatic powder coating applies powder to a substrate, followed by a curing cycle appropriate to the product. Material grade, preparation and powder type affect results. RAL describes reference colour, rather than corrosion protection or overall system performance.

Service environment

State indoor or outdoor use, exposure to water, sunlight, chemicals and installation conditions. Water-retaining surfaces and contact between dissimilar materials can change behaviour. Identical durability is not promised in every environment simply because a part is coated.

Texture and gloss

Describe shade, texture and gloss together. Fine-textured black and smooth glossy black can look different despite sharing the same RAL. For adjacent products, approve a sample and agree comparison criteria.

Coating system, colour and environment
SpecificationExample request field
MaterialS235JR, stainless steel or aluminium alloy
EnvironmentOutdoor, water / sun / identified agents
AppearanceRAL + smooth/textured + gloss
SystemPreparation and coating confirmed in quote
05 / Surface preparation before coating+

Cleaning

Grease, dirt, oxides and residues can affect adhesion or appearance. Preparation is selected for material and substrate condition. An apparently clean part may retain contamination; state material history, oils and previous coatings.

Cutting and welding

Check edges and weld areas before finishing. Dross, spatter, burrs and sharp corners do not automatically disappear under powder. A coating may emphasise substrate defects; request grinding or surface restoration where appearance requires it.

Special substrates

Galvanised materials, castings and porous surfaces may need particular assessment and preparation. Curing conditions must be compatible with the assembly. State adhesives, plastics and installed components before selecting the process.

Surface preparation before coating
Substrate conditionWhat to assess
OiledSuitable degreasing
Oxidised / rustedRemoval and substrate integrity
WeldedSpatter, marks, corners and flatness
Previously coatedCompatibility or removal
06 / Edges, cavities and surface access+

External edges

Very sharp edges can affect coating behaviour and are undesirable for handling. Provide appropriately prepared edges without changing functional areas. A dimensioned chamfer and simple deburring are distinct operations.

Internal corners and pockets

In electrostatic application, deep or shielded areas can be harder to coat uniformly. Do not assume a cavity interior receives the same layer as the outside face. If internal coating is critical, specify the area and verify process feasibility.

Enclosed volumes

Washing, drainage, drying, ventilation and heating require geometry checks. Process holes are established according to process and product. Avoid liquid-trapping cavities or configurations that cannot be cleaned or inspected; approve any geometry change before manufacturing.

Illustrative diagram: Edges, cavities and surface access
07 / Layer thickness and assembly clearances+

Specified thickness

Layer thickness is established for the coating product and system. We do not publish a universal thickness for every part. If critical, agree the range and measurement areas before quotation. Flat faces, edges and internal corners can have different conditions.

Calculating clearance

A slot coated on both opposing surfaces loses approximately twice the layer thickness from its clear width. A tab coated on both faces grows by the same effect. For a joint coated on both components, these effects accumulate.

Actual variation

The idealised calculation supports design but does not include all dimensional variation, burrs and local non-uniformity. Check part tolerances together with finishing-system tolerances. For a close fit, a finished sample is useful before production.

Illustrative diagram: Layer thickness and assembly clearances
08 / Masking, threads and contacts+

Assembly areas

Identify threads, bores, recesses, sealing surfaces and contact faces that must remain uncoated. Supplement the 3D model with a PDF view or masking map. Colour alone does not define whether an area requires masking.

Electrical contact

For grounding or conductive contact, state area and function. Ordinary powder is not assumed conductive. Make and verify the contact according to design requirements; an unmasked screw hole alone does not guarantee electrical continuity.

Operation sequence

Establish whether threads and bores are made before finishing with masking, or afterwards with protection restored where needed. Cleaning a thread after coating can remove local protection. Include this in the manufacturing route rather than at receiving.

Masking, threads and contacts
AreaInstruction
ThreadMasking or agreed later operation
Fit boreFinal dimension and protected area
SealingSurface and coating criterion
Electrical contactPosition, function and verification
Illustrative diagram: Masking, threads and contacts
09 / Hanging and the curing cycle+

Hanging points

The part must be supported and positioned during processing. Identify areas where hanging marks are accepted and whether process holes are allowed. For a cosmetic face, discussing hanging points before cutting can avoid a visible defect.

Temperature and time

Curing follows the product technical datasheet; oven air temperature and actual part temperature are different. Mass and thickness affect heating. A generic time cannot be applied to every assembly without checking the system.

Assembly compatibility

Assess sensitive components, plastics, adhesives, fillers and enclosed volumes before processing. State whether the part can be disassembled. Repair of a finished coating is not automatically equivalent to a complete cycle on a prepared substrate.

Illustrative diagram: Hanging and the curing cycle
10 / Appearance acceptance and measurement+

Sample and assessment conditions

For cosmetic products, agree a sample, viewing distance, lighting and orientation. Screens and photographs are not sufficiently stable colour and gloss references. For metallic effects or textures, orientation and process can influence perception.

Visible and hidden areas

Classify areas by appearance importance. A main visible face may have different requirements from an area hidden after assembly. Define whether hanging marks, local repairs or small imperfections are accepted and where; “perfect appearance” is not a measurable criterion.

Agreed inspection

If layer thickness, adhesion, colour or other tests are required, specify methods, areas and documents. A complete report is not assumed for every order. Results for a system or sample do not automatically replace verification of the requested batch.

Appearance acceptance and measurement
CheckTo agree
ColourSample and comparison conditions
AppearanceFaces, distance and acceptable defects
LayerRange and measurement points
TestsMethod, batch and requested report
11 / Packaging, repairs and maintenance+

Protect the final surface

Separators, edge protection and individual packaging reduce scratching risk. Avoid metal-to-metal contact and check whether film or packaging material can affect the finish. State whether products will be stored or installed immediately.

Installation

Screws, washers and tools can damage the layer. Plan contact faces and protective elements in the design. For outdoor coated parts, installation damage and water retention in joints can affect durability; assess installation details.

Repair and cleaning

If repair is needed, request a solution compatible with the applied system and required appearance level. Follow system cleaning instructions and avoid unvalidated aggressive agents. Local repair can differ in colour, texture or performance and must be accepted.

12 / Acceptance and packaging+

Checklist

Material; required system; service environment; RAL; texture; gloss; visible faces; masking; final dimensions; hanging points; acceptance criteria.

Production sample

For visible products, approve a representative sample and agree assessment conditions. Appearance requirements must be measurable and identical throughout the batch.

Protecting parts

State individual packaging, separators and sensitive areas. Avoid metal-to-metal contact in transport; include part-identification requirements.

Send your part for a quote ↗

English edition, 6 October 2026. Examples illustrate geometry and calculations. Materials, tooling, tolerances and finishes are confirmed for the specific project before production.

YOUR NEXT PROJECT

You have the drawing.
Let’s give it shape.

Upload your project

From a single part to a series. €50 minimum order.